MPC184-Weld## MPC184 Weld Joint Element Description

## MPC184 Weld Joint Input Data

### MPC184 Weld Joint Input Summary

## MPC184 Weld Joint Output Data

## MPC184 Weld Joint Assumptions and Restrictions

**Multipoint
Constraint Element: Weld Joint**

Compatible Products: – | Pro | Premium | Enterprise | Ent PP | Ent Solver | –

The MPC184 weld joint element is a two-node element that has all relative degrees of freedom fixed.

Set KEYOPT(1) = 13 to define a two-node weld joint element.

Figure 184weld.1: MPC184 Weld Joint Geometry shows the geometry and node locations for this element. Two nodes (I and J) define the element.

A local Cartesian coordinate system must be specified at the
first node, I, of the element. The local coordinate system specification
at the second node is optional. The local coordinate systems specified
at node I and J evolve with the rotations at the respective nodes.
Use the **SECJOINT** command to specify the identifiers
of the local coordinate systems.

Other input data that are common to all joint elements (material behavior, etc.) are described in "Joint Input Data" in the MPC184 element description.

**Note:** The weld joint may also be simulated by using the **CE** command. See the **CE** command description
for additional details.

This input summary applies to the weld joint element option of MPC184: KEYOPT(1) = 13.

**Nodes**I, J

**Note:**For a grounded joint element, specify either node I or node J in the element definition and leave the other node (the grounded node) blank.**Degrees of Freedom**UX, UY, UZ, ROTX, ROTY, ROTZ

**Real Constants**None

**Material Properties**None

**Surface Loads**None

**Body Loads**None

**Element Loads**None

**Special Features**Large deflection Linear perturbation **KEYOPT(1)**Element behavior:

**13 --**Weld joint element

The solution output associated with the element is in two forms:

Nodal displacements included in the overall nodal solution

Additional element output as shown in Table 184weld.1: MPC184 Weld Joint Element Output Definitions and Table 184weld.2: MPC184 Weld Joint Element - NMISC Output.

These tables use the following notation:

A colon (:) in the Name column indicates the item can be accessed
by the Component Name method [**ETABLE**, **ESOL**]. The O column indicates the availability of the
items in the file **Jobname.OUT**. The R column indicates
the availability of the items in the results file.

In either the O or R columns, Y indicates that the item is *always* available, a number refers to a table
footnote that describes when the item is *conditionally* available, and a - indicates that the item is *not* available.

**Table 184weld.1: MPC184 Weld Joint Element Output Definitions**

Name | Definition | O | R |
---|---|---|---|

EL | Element number | - | Y |

NODES | Element node numbers (I, J) | - | Y |

FX | Constraint force in X direction | - | Y |

FY | Constraint force in Y direction | - | Y |

FZ | Constraint force in Z direction | - | Y |

MX | Constraint moment in X direction | - | Y |

MY | Constraint moment in Y direction | - | Y |

MZ | Constraint moment in Z direction | - | Y |

The following table shows additional non-summable miscellaneous (NMISC) output available for the weld joint element.

**Note:** This output is intended for use in the ANSYS Workbench program
to track the evolution of local coordinate systems specified at the
nodes of joint elements.

**Table 184weld.2: MPC184 Weld Joint Element - NMISC Output**

Name | Definition | O | R |
---|---|---|---|

E1X-I, E1Y-I, E1Z-I | X, Y, Z components
of the evolved e_{1} axis at node I | - | Y |

E2X-I, E2Y-I, E2Z-I | X, Y, Z components of the evolved e_{2} axis at node I | - | Y |

E3X-I, E3Y-I, E3Z-I | X, Y, Z components of the
evolved e_{3} axis at node I | - | Y |

E1X-J, E1Y-J, E1Z-J | X, Y, Z components of the evolved e_{1} axis
at node J | - | Y |

E2X-J, E2Y-J, E2Z-J | X, Y, Z components of the evolved
e_{2} axis at node J | - | Y |

E3X-J, E3Y-J, E3Z-J | X, Y,
Z components of the evolved e_{3} axis at node
J | - | Y |

JFX, JFY, JFZ | Constraint forces expressed in the evolved coordinate system specified at node I | - | Y |

JMX, JMY, JMZ | Constraint moments expressed in the evolved coordinate system specified at node I | - | Y |

Table 184weld.3: MPC184 Weld Joint Item and Sequence Numbers - SMISC Items and Table 184weld.4: MPC184 Weld Joint Item and Sequence Numbers - NMISC Items list output available via the **ETABLE** command using the Sequence Number method. See The General Postprocessor (POST1) in the *Basic Analysis Guide* and The Item and Sequence Number Table for further information.
The table uses the following notation:

**Name**output quantity as defined in the Element Output Definitions table.

**Item**predetermined Item label for

**ETABLE**command**E**sequence number for single-valued or constant element data

**Table 184weld.4: MPC184 Weld Joint Item and Sequence Numbers - NMISC Items**

Output Quantity Name | ETABLE and ESOL Command Input | |
---|---|---|

Item | E | |

E1X-I | NMISC | 1 |

E1Y-I | NMISC | 2 |

E1Z-I | NMISC | 3 |

E2X-I | NMISC | 4 |

E2Y-I | NMISC | 5 |

E2Z-I | NMISC | 6 |

E3X-I | NMISC | 7 |

E3Y-I | NMISC | 8 |

E3Z-I | NMISC | 9 |

E1X-J | NMISC | 10 |

E1Y-J | NMISC | 11 |

E1Z-J | NMISC | 12 |

E2X-J | NMISC | 13 |

E2Y-J | NMISC | 14 |

E2Z-J | NMISC | 15 |

E3X-J | NMISC | 16 |

E3Y-J | NMISC | 17 |

E3Z-J | NMISC | 18 |

JFX | NMISC | 19 |

JFY | NMISC | 20 |

JFZ | NMISC | 21 |

JMX | NMISC | 22 |

JMY | NMISC | 23 |

JMZ | NMISC | 24 |

Boundary conditions cannot be applied on the nodes forming the weld joint.

Rotational degrees of freedom are activated at the nodes forming the element. When these elements are used in conjunction with solid elements, the rotational degrees of freedom must be suitably constrained. Since boundary conditions cannot be applied to the nodes of the weld joint, a beam or shell element with very weak stiffness may be used with the underlying solid elements at the nodes forming the joint element to avoid any rigid body modes.

Stops (

**SECSTOP**) and locks (**SECLOCK**) are not applicable to this element.In a nonlinear analysis, the components of relative motion are accumulated over all the substeps. It is essential that the substep size be restricted such that these rotations in a given substep are less than π for the values to be accumulated correctly.

The element currently does not support birth or death options.

The equation solver (

**EQSLV**) must be the sparse solver or the PCG solver. The command**PCGOPT**,,,,,,,ON is also required in order to use the PCG solver.The element coordinate system (

**/PSYMB**,ESYS) is not relevant.