LINK11


Linear Actuator

Compatible Products: – | – | – | Enterprise | Ent PP | Ent Solver | –

LINK11 Element Description

LINK11 may be used to model hydraulic cylinders and other applications undergoing large rotations. The element is a uniaxial tension-compression element with three degrees of freedom at each node: translations in the nodal x, y, and z directions. No bending or twist loads are considered. See LINK11 in the Mechanical APDL Theory Reference for more details about this element.

Figure 11.1:  LINK11 Geometry

LINK11 Geometry

LINK11 Input Data

The geometry and node locations for the element are shown in Figure 11.1: LINK11 Geometry. The element is defined by two nodes, a stiffness, viscous damping, and mass. The element initial length Lo and orientation are determined from the node locations.

Element loads are described in Nodal Loading. The stroke (length) is defined through the surface load input using the PRES label. The stroke is relative to the zero force position of the element. A force may be defined in the same manner as an alternate to the stroke.

A summary of the element input is given below. A general description of element input is given in Element Input.

LINK11 Input Summary

Nodes

I, J

Degrees of Freedom

UX, UY, UZ

Real Constants
K - Stiffness (force/length)
C - Viscous damping coefficient (force*time/length)
M - Mass (force*time2/length)
Material Properties

MP command: BETD, ALPD

Surface Loads
Pressures -- 
face 1 - Stroke
face 2 - Axial Force
Body Loads

None

Special Features
Birth and death
Large deflection
Stress stiffening
KEYOPTs

None

LINK11 Output Data

The solution output associated with the element is in two forms:

A general description of solution output is given in Solution Output. See the Basic Analysis Guide for ways to view results.

The Element Output Definitions table uses the following notation:

A colon (:) in the Name column indicates that the item can be accessed by the Component Name method (ETABLE, ESOL). The O column indicates the availability of the items in the file Jobname.OUT. The R column indicates the availability of the items in the results file.

In either the O or R columns, “Y” indicates that the item is always available, a number refers to a table footnote that describes when the item is conditionally available, and “-” indicates that the item is not available.

Table 11.1:  LINK11 Element Output Definitions

NameDefinitionOR
ELElement NumberYY
NODESNodes - I, JYY
ILENInitial element lengthYY
CLENCurrent element length (this time step)YY
FORCEAxial force (spring force)YY
DFORCEDamping forceYY
STROKEApplied stroke (element load)YY
MSTROKEMeasured strokeYY

Table 11.2: LINK11 Item and Sequence Numbers lists output available through the ETABLE command using the Sequence Number method. The following notation is used in Table 11.2: LINK11 Item and Sequence Numbers:

Name

output quantity as defined in Table 11.1: LINK11 Element Output Definitions

Item

predetermined Item label for ETABLE command

E

sequence number for single-valued or constant element data

Table 11.2:  LINK11 Item and Sequence Numbers

Output Quantity NameETABLE and ESOL Command Input
ItemE
FORCESMISC1
ILENNMISC1
CLENNMISC2
STROKENMISC3
MSTROKENMISC4
DFORCENMISC5

LINK11 Assumptions and Restrictions

  • The element must not have a zero length.

  • The element assumes a straight line, axially loaded at the ends.

  • A twist (torsion) about the element x-axis (defined from node I to node J) has no effect.

  • No bending of the element is considered, as in a pin-jointed structure.

  • The mass is equally divided between the nodes.

  • Only the lumped mass matrix is available.

  • Surface load pressure indicators are not displayed for element or node plots.

LINK11 Product Restrictions

There are no product-specific restrictions for this element.


Release 18.2 - © ANSYS, Inc. All rights reserved.