PLNSOL, Item, Comp, KUND, Fact, FileID
Displays results as continuous contours.

Compatible Products: – | Pro | Premium | Enterprise | Ent PP | Ent Solver | DYNA


Label identifying the item. Valid item labels are shown in the table below. Some items also require a component label.


Component of the item (if required). Valid component labels are shown in the table below.


Undisplaced shape key:



Do not overlay undeformed structure display.



Overlay displaced contour plot with undeformed display (appearance is system-dependent).



Overlay displaced contour plot with undeformed edge display (appearance is system-dependent).


Scale factor for 2-D display for contact items. Default value is 1. A negative scaling factor inverts the display.


The file index number (obtained via NLDIAG,NRRE,ON). Valid only for Item = NRRE.


PLNSOL displays the solution results as continuous contours across element boundaries for the selected nodes and elements.

For example, PLNSOL,S,X displays the X component of stress S (that is, the SX stress component). Various element results depend upon the recalculation method and the selected results location (AVPRIN, RSYS, LAYER, SHELL, and NSEL).

Contours are determined by linear interpolation within each element from the nodal values, averaged at a node whenever two or more elements connect to the same node. (The exception is FMAG, which is summed at the node.)

For PowerGraphics displays (/GRAPHICS,POWER), results are plotted for the model exterior surface only. Items marked [2] are not supported by PowerGraphics.

To plot midside nodes, first issue /EFACET,2.

Table 210:  PLNSOL - Valid Item and Component Labels

General Item and Component Labels PLNSOL, Lab, Item, Comp
Valid item and component labels for nodal degree of freedom results are:
UX, Y, Z, SUMX, Y, or Z structural displacement or vector sum.
ROTX, Y, Z, SUMX, Y, or Z structural rotation or vector sum.
TEMP[1] Temperature.
PRES Pressure.
VOLT Electric potential.
MAG Magnetic scalar potential.
CONC Concentration. [2]
X, Y, or Z fluid velocity or vector sum in a fluid analysis, or
X, Y, or Z velocity or vector sum in an ANSYS LS-DYNA analysis.
X, Y, or Z magnetic vector potential or vector sum in an electromagnetic analysis, or
X, Y, or Z acceleration or vector sum in an ANSYS LS-DYNA analysis.
VELX, Y, Z, SUMX, Y, or Z velocity or vector sum in a structural transient dynamic analysis (ANTYPE,TRANS). 
ACCX, Y, Z, SUMX, Y, or Z acceleration or vector sum in a structural transient dynamic analysis (ANTYPE,TRANS).
OMGX, Y, Z, SUMX, Y, or Z rotational velocity or vector sum in a structural transient dynamic analysis (ANTYPE,TRANS). 
DMGX, Y, Z, SUMX, Y, or Z rotational acceleration or vector sum in a structural transient dynamic analysis (ANTYPE,TRANS).
WARP Warping.
NRREFX, FY, FZ, FNRM, MX, MY, MZ, MNRM Plot the Newton-Raphson residuals from the file you obtained via the NLDIAG,NRRE,ON command. The FNRM and MNRM labels are computed as the square root of the sum of the squares of the residual component forces or moments (FX,FY,FZ, MX, MY, MZ). [5]
 When KUND = 0, use the absolute value of the residual from the files (default).
SPL Sound pressure level.
SPLA A-weighted sound pressure level (dBA).
VNS Normal velocity on the structural surface. [10]
Valid item and component labels for element results are:
SX, Y, Z, XY, YZ, XZComponent stress.
1, 2, 3Principal stress.
INTStress intensity.
EQVEquivalent stress.
EPELX, Y, Z, XY, YZ, XZComponent elastic strain.
1, 2, 3Principal elastic strain.
INTElastic strain intensity.
EQVElastic equivalent strain.
EPTHX, Y, Z, XY, YZ, XZComponent thermal strain.
1, 2, 3Principal thermal strain.
INTThermal strain intensity.
EQVThermal equivalent strain.
EPPLX, Y, Z, XY, YZ, XZComponent plastic strain.
1, 2, 3Principal plastic strain.
INTPlastic strain intensity.
EQVPlastic equivalent strain.
EPCRX, Y, Z, XY, YZ, XZComponent creep strain.
1, 2, 3Principal creep strain.
INTCreep strain intensity.
EQVCreep equivalent strain.
EPSW Swelling strain.
EPTOX, Y, Z, XY, YZ, XZComponent total mechanical strain (EPEL + EPPL + EPCR).
1, 2, 3Principal total mechanical strain.
INTTotal mechanical strain intensity.
EQVTotal mechanical equivalent strain.
EPTTX, Y, Z, XY, YZ, XZComponent total mechanical and thermal and swelling strain (EPEL + EPPL + EPCR + EPTH + EPSW).
1, 2, 3Principal total mechanical and thermal and swelling strain.
INTTotal mechanical and thermal and swelling strain intensity.
EQVTotal mechanical and thermal and swelling equivalent strain.
EPDIX, Y, Z, XY, YZ, XZComponent diffusion strain. [2]
1, 2, 3Principal diffusion strain.
INTDiffusion strain intensity.
EQVDiffusion equivalent strain.
ESIGX,Y,Z,XY,YZ,ZXComponents of Biot’s effective stress.
1, 2, 3Principal stresses of Biot’s effective stress.
INTStress intensity of Biot’s effective stress.
EQVEquivalent stress of Biot’s effective stress.
DPARTPORTotal porosity (Gurson material model).
GPORPorosity due to void growth.
NPORPorosity due to void nucleation.
NLSEPLEquivalent stress (from stress-strain curve).
SRATStress state ratio.
HPRESHydrostatic pressure.
EPEQAccumulated equivalent plastic strain.
CREQAccumulated equivalent creep strain.
PSVPlastic state variable.
PLWKPlastic work/volume.
SENDELASTICElastic strain energy density.
PLASTIC Plastic strain energy density.
CREEPCreep strain energy density.
DAMAGEDamage strain energy density.
VDAMViscoelastic dissipation energy density.
VREGVisco-regularization strain energy density.
ENTOTotal strain energy density.
CDMDMGDamage variable.
LMMaximum previous strain energy for virgin material.
FAILMAXMaximum of all active failure criteria defined at the current location. (See FCTYP.) [2][6]
EMAXMaximum Strain Failure Criterion. [2][6]
SMAXMaximum Stress Failure Criterion. [2][6]
TWSITsai-Wu Strength Index Failure Criterion. [2][6]
TWSRInverse of Tsai-Wu Strength Ratio Index Failure Criterion. [2][6]
HFIBHashin Fiber Failure Criterion. [2][6][8]
HMATHashin Matrix Failure Criterion. [2][6][8]
PFIBPuck Fiber Failure Criterion. [2][6][8]
PMATPuck Matrix Failure Criterion. [2][6][8]
L3FBLaRc03 Fiber Failure Criterion. [2][6][8]
L3MTLaRc03 Matrix Failure Criterion. [2][6][8]
L4FBLaRc04 Fiber Failure Criterion. [2][6][8]
L4MTLaRc04 Matrix Failure Criterion. [2][6][8]
USR1, USR2, ..., USR9User-defined failure criteria. [2][6][7][8]
PFCMAX [9]Maximum of all failure criteria defined at current location.
FT [9]Fiber tensile failure criteria.
FC [9]Fiber compressive failure criteria.
MT [9]Matrix tensile failure criteria.
MC [9]Matrix compressive failure criteria.
PDMGSTATDamage status (0 = undamaged, 1 = damaged, 2 = completely damaged).
FTFiber tensile damage variable.
FCFiber compressive damage variable.
MTMatrix tensile damage variable.
MCMatrix compressive damage variable.
SShear damage variable (S).
SEDEnergy dissipated per unit volume.
SEDVEnergy per unit volume due to viscous damping.
SVAR1, 2, 3, ... NState variable. [2]
GKSX, XY, XZGasket component stress.
GKDX, XY, XZGasket component total closure.
GKDIX, XY, XZGasket component total inelastic closure.
GKTHX, XY, XZGasket component thermal closure.
SSX, XY, XZInterface traction (stress).
SDX, XY, XZInterface separation.
FICTTEMPFictive temperature.
For contact results PowerGraphics is applicable for 3-D models only.
CONT[3]STATContact status[4]:
3 = closed and sticking
2 = closed and sliding
1 = open but near contact
0 = open and not near contact
PENEContact penetration.
PRESContact pressure.
SFRICContact friction stress.
STOTContact total stress (pressure plus friction).
SLIDEContact sliding distance.
GAPContact gap distance.
FLUXTotal heat flux at contact surface.
CNOSTotal number of contact status changes during substep.
FPRSFluid penetration pressure.
TGX, Y, Z, SUMComponent thermal gradient or vector sum.
TFX, Y, Z, SUMComponent thermal flux or vector sum.
PGX, Y, Z, SUMComponent pressure gradient or vector sum.
EFX, Y, Z, SUMComponent electric field or vector sum.
DX, Y, Z, SUMComponent electric flux density or vector sum.
HX, Y, Z, SUMComponent magnetic field intensity or vector sum.
BX, Y, Z, SUMComponent magnetic flux density or vector sum.
CGX, Y, Z, SUMComponent concentration gradient or vector sum. [2]
DFX, Y, Z, SUMComponent diffusion flux density or vector sum. [2]
FMAGX, Y, Z, SUMComponent electromagnetic force or vector sum. [2]
JCX, Y, Z, SUMConduction current density for elements that support conduction current calculation. Components (X, Y, Z) and vector sum (SUM). [2].
BFETEMPBody temperatures (calculated from applied temperatures) as used in solution (area and volume elements only).
PMSVVRAT, PPRE, DSAT, RPERVoid volume ratio, pore pressure, degree of saturation, and relative permeability for coupled pore-pressure CPT elements.
NSX, Y, Z, XY, YZ, XZNominal strain for hyperelastic material, reported in the current configuration (unaffected by RSYS).
MPLADMAC, DMAXMicroplane damage, macroscopic and maximum values.

  1. For SHELL131 and SHELL132 elements with KEYOPT(3) = 0 or 1, use the labels TBOT, TE2, TE3, . . ., TTOP instead of TEMP to view the individual temperature degree of freedom. When other thermal elements are included in the model, deselect them to avoid plotting undefined information. To view all temperatures in the same plot, set /ESHAPE,1 and /GRAPHICS,POWER and issue PLNSOL,TEMP.

  2. Not supported by PowerGraphics

  3. For the CONT items for elements CONTA171 through CONTA177, the reported data is averaged across the element. To obtain a more meaningful STAT value, use the PLESOL command.

  4. For MPC-based contact definitions, the value of STAT can be negative. This indicates that one or more contact constraints were intentionally removed to prevent overconstraint. STAT = -3 is used for MPC bonded contact; STAT = -2 is used for MPC no-separation contact.

  5. When plotting Newton-Raphson residual items (Item = NRRE) from a file on the deformed geometry, the displacements are based on the current set of results in the database. These displacements may not correspond to the loadstep and substep in the .nrxxxxx file. (For more information about .nrxxxxx files and nonlinear diagnostics postprocessing, see the description of the NLDPOST command and Performing Nonlinear Diagnostics.)

  6. Works only if failure criteria information is provided (FC and TB).

  7. Works only if user failure criteria routine is provided.

  8. Must be added via FCTYP first.

  9. Failure criteria are based on the effective stresses in the damaged material.

  10. Only valid for SHELL181, SOLID185, SOLID186, SOLID187, SOLSH190, and SHELL281.

Menu Paths

Main Menu>Drop Test>Animate Results
Main Menu>General Postproc>Plot Results>Contour Plot>Nodal Solu
Utility Menu>Plot>Results>Contour Plot>Nodal Solution
Utility Menu>PlotCtrls>Animate>Animate Over Results
Utility Menu>PlotCtrls>Animate>Animate Over Time
Utility Menu>PlotCtrls>Animate>Deformed Results
Utility Menu>PlotCtrls>Animate>Dynamic Results
Utility Menu>PlotCtrls>Animate>Isosurfaces
Utility Menu>PlotCtrls>Animate>Mode Shape
Utility Menu>PlotCtrls>Animate>Q-Slice Contours
Utility Menu>PlotCtrls>Animate>Time-harmonic

Release 18.2 - © ANSYS, Inc. All rights reserved.