**PLNSOL**, * Item*,

`Comp`

`KUND`

`Fact`

`FileID `

Compatible Products: – | Pro | Premium | Enterprise | Ent PP | Ent Solver | DYNA

`Item`

Label identifying the item. Valid item labels are shown in the table below. Some items also require a component label.

`Comp`

Component of the item (if required). Valid component labels are shown in the table below.

`KUND`

Undisplaced shape key:

**0**—

Do not overlay undeformed structure display.

**1**—

Overlay displaced contour plot with undeformed display (appearance is system-dependent).

**2**—

Overlay displaced contour plot with undeformed edge display (appearance is system-dependent).

`Fact`

Scale factor for 2-D display for contact items. Default value is 1. A negative scaling factor inverts the display.

`FileID`

The file index number (obtained via

**NLDIAG**,NRRE,ON). Valid only for= NRRE.`Item`

**PLNSOL** displays the solution results as continuous contours across element
boundaries for the selected nodes and elements.

For example, **PLNSOL**,S,X displays the X component of stress S (that is,
the SX stress component). Various element results depend upon the recalculation method and the
selected results location (**AVPRIN**, **RSYS**,
**LAYER**, **SHELL**, and **NSEL**).

Contours are determined by linear interpolation within each element from the nodal values, averaged at a node whenever two or more elements connect to the same node. (The exception is FMAG, which is summed at the node.)

For PowerGraphics displays (**/GRAPHICS**,POWER), results are plotted for the
model exterior surface only. Items marked [2] are not
supported by PowerGraphics.

To plot midside nodes, first issue **/EFACET**,2.

**Table 210: PLNSOL - Valid Item and Component Labels**

General Item and Component Labels
PLNSOL, `Lab, Item, Comp` | ||||||
---|---|---|---|---|---|---|

Item | Comp | Description | ||||

Valid item and
component labels for nodal degree of freedom results are: | ||||||

U | X, Y, Z, SUM | X, Y, or Z structural displacement or vector sum. | ||||

ROT | X, Y, Z, SUM | X, Y, or Z structural rotation or vector sum. | ||||

TEMP[1] | Temperature. | |||||

PRES | Pressure. | |||||

VOLT | Electric potential. | |||||

MAG | Magnetic scalar potential. | |||||

CONC | Concentration. [2] | |||||

V | X, Y, Z, SUM |
| ||||

A | X, Y, Z, SUM |
| ||||

VEL | X, Y, Z, SUM | X, Y, or Z velocity or vector sum in a structural transient dynamic analysis
(ANTYPE,TRANS). | ||||

ACC | X, Y, Z, SUM | X, Y, or Z acceleration or vector sum in a structural transient dynamic
analysis (ANTYPE,TRANS). | ||||

OMG | X, Y, Z, SUM | X, Y, or Z rotational velocity or vector sum in a structural transient
dynamic analysis (ANTYPE,TRANS). | ||||

DMG | X, Y, Z, SUM | X, Y, or Z rotational acceleration or vector sum in a structural transient
dynamic analysis (ANTYPE,TRANS). | ||||

WARP | Warping. | |||||

NRRE | FX, FY, FZ, FNRM, MX, MY, MZ, MNRM | Plot the Newton-Raphson residuals from the file you obtained
via the NLDIAG,NRRE,ON command. The FNRM and MNRM labels are computed as
the square root of the sum of the squares of the residual component forces or moments
(FX,FY,FZ, MX, MY, MZ). [5] | ||||

When KUND = 0, use the absolute value of the residual from the files (default). | ||||||

SPL | Sound pressure level. | |||||

SPLA | A-weighted sound pressure level (dBA). | |||||

VNS | Normal velocity on the structural surface. [10] | |||||

Valid item and
component labels for element results are: | ||||||

S | X, Y, Z, XY, YZ, XZ | Component stress. | ||||

1, 2, 3 | Principal stress. | |||||

INT | Stress intensity. | |||||

EQV | Equivalent stress. | |||||

EPEL | X, Y, Z, XY, YZ, XZ | Component elastic strain. | ||||

1, 2, 3 | Principal elastic strain. | |||||

INT | Elastic strain intensity. | |||||

EQV | Elastic equivalent strain. | |||||

EPTH | X, Y, Z, XY, YZ, XZ | Component thermal strain. | ||||

1, 2, 3 | Principal thermal strain. | |||||

INT | Thermal strain intensity. | |||||

EQV | Thermal equivalent strain. | |||||

EPPL | X, Y, Z, XY, YZ, XZ | Component plastic strain. | ||||

1, 2, 3 | Principal plastic strain. | |||||

INT | Plastic strain intensity. | |||||

EQV | Plastic equivalent strain. | |||||

EPCR | X, Y, Z, XY, YZ, XZ | Component creep strain. | ||||

1, 2, 3 | Principal creep strain. | |||||

INT | Creep strain intensity. | |||||

EQV | Creep equivalent strain. | |||||

EPSW | Swelling strain. | |||||

EPTO | X, Y, Z, XY, YZ, XZ | Component total mechanical strain (EPEL + EPPL + EPCR). | ||||

1, 2, 3 | Principal total mechanical strain. | |||||

INT | Total mechanical strain intensity. | |||||

EQV | Total mechanical equivalent strain. | |||||

EPTT | X, Y, Z, XY, YZ, XZ | Component total mechanical and thermal
and swelling strain (EPEL + EPPL + EPCR + EPTH + EPSW). | ||||

1, 2, 3 | Principal total mechanical and thermal
and swelling strain. | |||||

INT | Total mechanical and thermal and
swelling strain intensity. | |||||

EQV | Total mechanical and thermal and
swelling equivalent strain. | |||||

EPDI | X, Y, Z, XY, YZ, XZ | Component diffusion strain. [2] | ||||

1, 2, 3 | Principal diffusion strain. | |||||

INT | Diffusion strain intensity. | |||||

EQV | Diffusion equivalent strain. | |||||

ESIG | X,Y,Z,XY,YZ,ZX | Components of Biot’s effective stress. | ||||

1, 2, 3 | Principal stresses of Biot’s effective stress. | |||||

INT | Stress intensity of Biot’s effective stress. | |||||

EQV | Equivalent stress of Biot’s effective stress. | |||||

DPAR | TPOR | Total porosity (Gurson material model). | ||||

GPOR | Porosity due to void growth. | |||||

NPOR | Porosity due to void nucleation. | |||||

NL | SEPL | Equivalent stress (from stress-strain curve). | ||||

SRAT | Stress state ratio. | |||||

HPRES | Hydrostatic pressure. | |||||

EPEQ | Accumulated equivalent plastic strain. | |||||

CREQ | Accumulated equivalent creep strain. | |||||

PSV | Plastic state variable. | |||||

PLWK | Plastic work/volume. | |||||

SEND | ELASTIC | Elastic strain energy density. | ||||

PLASTIC | Plastic strain energy density. | |||||

CREEP | Creep strain energy density. | |||||

DAMAGE | Damage strain energy density. | |||||

VDAM | Viscoelastic dissipation energy density. | |||||

VREG | Visco-regularization strain energy density. | |||||

ENTO | Total strain energy density. | |||||

CDM | DMG | Damage variable. | ||||

LM | Maximum previous strain energy for virgin material. | |||||

FAIL | MAX | Maximum of all active failure criteria defined at the current location. (See
FCTYP.) [2][6] | ||||

EMAX | Maximum Strain Failure Criterion. [2][6] | |||||

SMAX | Maximum Stress Failure Criterion. [2][6] | |||||

TWSI | Tsai-Wu Strength Index Failure Criterion. [2][6] | |||||

TWSR | Inverse of Tsai-Wu Strength Ratio Index Failure Criterion. [2][6] | |||||

HFIB | Hashin Fiber Failure Criterion. [2][6][8] | |||||

HMAT | Hashin Matrix Failure Criterion. [2][6][8] | |||||

PFIB | Puck Fiber Failure Criterion. [2][6][8] | |||||

PMAT | Puck Matrix Failure Criterion. [2][6][8] | |||||

L3FB | LaRc03 Fiber Failure Criterion. [2][6][8] | |||||

L3MT | LaRc03 Matrix Failure Criterion. [2][6][8] | |||||

L4FB | LaRc04 Fiber Failure Criterion. [2][6][8] | |||||

L4MT | LaRc04 Matrix Failure Criterion. [2][6][8] | |||||

USR1, USR2, ..., USR9 | User-defined failure criteria. [2][6][7][8] | |||||

PFC | MAX [9] | Maximum of all failure criteria defined at current location. | ||||

FT [9] | Fiber tensile failure criteria. | |||||

FC [9] | Fiber compressive failure criteria. | |||||

MT [9] | Matrix tensile failure criteria. | |||||

MC [9] | Matrix compressive failure criteria. | |||||

PDMG | STAT | Damage status (0 = undamaged, 1 = damaged, 2 = completely damaged). | ||||

FT | Fiber tensile damage variable. | |||||

FC | Fiber compressive damage variable. | |||||

MT | Matrix tensile damage variable. | |||||

MC | Matrix compressive damage variable. | |||||

S | Shear damage variable (S). | |||||

SED | Energy dissipated per unit volume. | |||||

SEDV | Energy per unit volume due to viscous damping. | |||||

SVAR | 1, 2, 3, ... N | State variable. [2] | ||||

GKS | X, XY, XZ | Gasket component stress. | ||||

GKD | X, XY, XZ | Gasket component total closure. | ||||

GKDI | X, XY, XZ | Gasket component total inelastic closure. | ||||

GKTH | X, XY, XZ | Gasket component thermal closure. | ||||

SS | X, XY, XZ | Interface traction (stress). | ||||

SD | X, XY, XZ | Interface separation. | ||||

FICT | TEMP | Fictive temperature. | ||||

For contact
results PowerGraphics is applicable for 3-D models only. | ||||||

CONT[3] | STAT | Contact status[4]:
| ||||

PENE | Contact penetration. | |||||

PRES | Contact pressure. | |||||

SFRIC | Contact friction stress. | |||||

STOT | Contact total stress (pressure plus friction). | |||||

SLIDE | Contact sliding distance. | |||||

GAP | Contact gap distance. | |||||

FLUX | Total heat flux at contact surface. | |||||

CNOS | Total number of contact status changes during substep. | |||||

FPRS | Fluid penetration pressure. | |||||

TG | X, Y, Z, SUM | Component thermal gradient or vector sum. | ||||

TF | X, Y, Z, SUM | Component thermal flux or vector sum. | ||||

PG | X, Y, Z, SUM | Component pressure gradient or vector sum. | ||||

EF | X, Y, Z, SUM | Component electric field or vector sum. | ||||

D | X, Y, Z, SUM | Component electric flux density or vector sum. | ||||

H | X, Y, Z, SUM | Component magnetic field intensity or vector sum. | ||||

B | X, Y, Z, SUM | Component magnetic flux density or vector sum. | ||||

CG | X, Y, Z, SUM | Component concentration gradient or vector sum. [2] | ||||

DF | X, Y, Z, SUM | Component diffusion flux density or vector sum. [2] | ||||

FMAG | X, Y, Z, SUM | Component electromagnetic force or vector sum. [2] | ||||

JC | X, Y, Z, SUM | Conduction current density for elements that support conduction current calculation. Components (X, Y, Z) and vector sum (SUM). [2]. | ||||

BFE | TEMP | Body temperatures (calculated from applied temperatures) as used in solution (area and volume elements only). | ||||

PMSV | VRAT, PPRE, DSAT, RPER | Void volume ratio, pore pressure, degree of saturation, and relative permeability for coupled pore-pressure CPT elements. | ||||

NS | X, Y, Z, XY, YZ, XZ | Nominal strain for
hyperelastic material, reported in the current configuration (unaffected by
RSYS). | ||||

MPLA | DMAC, DMAX | Microplane damage, macroscopic and maximum values. |

For SHELL131 and SHELL132 elements with KEYOPT(3) = 0 or 1, use the labels TBOT, TE2, TE3, . . ., TTOP instead of TEMP to view the individual temperature degree of freedom. When other thermal elements are included in the model, deselect them to avoid plotting undefined information. To view all temperatures in the same plot, set

**/ESHAPE**,1 and**/GRAPHICS**,POWER and issue**PLNSOL**,TEMP.For the CONT items for elements CONTA171 through CONTA177, the reported data is averaged across the element. To obtain a more meaningful STAT value, use the

**PLESOL**command.For MPC-based contact definitions, the value of STAT can be negative. This indicates that one or more contact constraints were intentionally removed to prevent overconstraint. STAT = -3 is used for MPC bonded contact; STAT = -2 is used for MPC no-separation contact.

When plotting Newton-Raphson residual items (

= NRRE) from a file on the deformed geometry, the displacements are based on the current set of results in the database. These displacements may not correspond to the loadstep and substep in the`Item`

**.nr**file. (For more information about`xxxxx`

**.nr**files and nonlinear diagnostics postprocessing, see the description of the`xxxxx`

**NLDPOST**command and Performing Nonlinear Diagnostics.)Works only if failure criteria information is provided (

**FC**and**TB**).Must be added via

**FCTYP**first.Failure criteria are based on the effective stresses in the damaged material.

Only valid for SHELL181, SOLID185, SOLID186, SOLID187, SOLSH190, and SHELL281.