*VPUT, ParR, Entity, ENTNUM, Item1, IT1NUM, Item2, IT2NUM, KLOOP
Restores array parameter values into the ANSYS database.
ParRThe name of the input vector array parameter. See *SET for name restrictions. The parameter must exist as a dimensioned array [*DIM] with data input.
EntityEntity keyword. Valid keywords are shown for Entity = in the table below.
ENTNUMThe number of the entity (as shown for ENTNUM= in the table below).
Item1The name of a particular item for the given entity.
Valid items are as shown in the Item1 columns
of the table below.
IT1NUMThe number (or label) for the specified Item1 (if any). Valid IT1NUM values are as shown in the IT1NUM columns
of the table below. Some Item1 labels
do not require an IT1NUM value.
Item2, IT2NUMA second set of item labels and numbers to further qualify the item for which data is to be stored. Most items do not require this level of information.
KLOOPField to be looped on:
Loop on the ENTNUM field (default).
Loop on the Item1 field.
Loop on the IT1NUM field. Successive items are as shown with IT1NUM.
Loop on the Item2 field.
Loop on the IT2NUM field. Successive items are as shown with IT2NUM.
The *VPUT command is not supported for PowerGraphics displays. Inconsistent results may be obtained if this command is not used in /GRAPHICS, FULL.
Plot and print operations entered via the GUI () incorporate the AVPRIN command. This means that the principal and equivalent values are recalculated. If you use *VPUT to put data back into the database, issue the plot commands from the command line to preserve your data.
This operation is basically the inverse of the *VGET operation. Vector items are put directly (without any coordinate
system transformation) into the ANSYS database. Items can only replace
existing items of the database and not create new items. Degree of
freedom results that are replaced in the database are available for
all subsequent postprocessing operations. Other results are changed
temporarily and are available mainly for the immediately following
print and display operations. The vector specification *VCUM does not apply to this command. The valid labels for the location
fields (Entity, ENTNUM, Item1, and IT1NUM) are listed below. Item2 and IT2NUM are not currently used. Not all items from
the *VGET list are allowed on *VPUT since putting values into some locations could cause the database
to be inconsistent.
This command is valid in any processor.
Table 240: *VPUT - POST1 Items
Entity = NODE, ENTNUM = n (node number) | ||
|---|---|---|
| Item1 | IT1NUM | Description |
| Valid labels for nodal degree of freedom results are: | ||
| U | X, Y, Z | X, Y, or Z structural displacement. |
| ROT | X, Y, Z | X, Y, or Z structural rotation. |
| TEMP | Temperature. For SHELL131 and SHELL132 elements with KEYOPT(3) = 0 or 1, use TBOT, TE2, TE3, . . ., TTOP instead of TEMP. Alternative get functions: TEMP(N), TBOT(N), TE2(N), etc. | |
| PRES | Pressure. | |
| VOLT | Electric potential. | |
| MAG | Magnetic scalar potential. | |
| V | X, Y, Z | X, Y, or Z fluid velocity. X, Y, or Z nodal velocity in a transient structural analysis (LS-DYNA analysis or analysis with ANTYPE,TRANS). |
| A | X, Y, Z | X, Y, or Z magnetic vector potential. X, Y, or Z nodal acceleration in a transient structural analysis (LS-DYNA analysis or analysis with ANTYPE,TRANS). |
| CONC | Concentration. | |
| CURR | Current. | |
| EMF | Electromotive force drop. | |
| Valid labels for element nodal results are: | ||
| Item1 | IT1NUM | Description |
| S | X, Y, Z, XY, YZ, XZ | Component stress. |
| " | 1, 2, 3 | Principal stress. |
| " | INT, EQV | Stress intensity or equivalent stress. |
| EPTO | X, Y, Z, XY, YZ, XZ | Component total strain (EPEL + EPPL + EPCR). |
| " | 1,2,3 | Principal total strain. |
| " | INT, EQV | Total strain intensity or total equivalent strain. |
| EPEL | X, Y, Z, XY, YZ, XZ | Component elastic strain. |
| " | 1, 2, 3 | Principal elastic strain. |
| " | INT, EQV | Elastic strain intensity or elastic equivalent strain. |
| EPPL | X, Y, Z, XY, YZ, XZ | Component plastic strain. |
| " | 1,2,3 | Principal plastic strain. |
| " | INT, EQV | Plastic strain intensity or plastic equivalent strain. |
| EPCR | X, Y, Z, XY, YZ, XZ | Component creep strain. |
| " | 1, 2, 3 | Principal creep strain. |
| " | INT, EQV | Creep strain intensity or creep equivalent strain. |
| EPTH | X, Y, Z, XY, YZ, XZ | Component thermal strain. |
| " | 1, 2, 3 | Principal thermal strain. |
| " | INT, EQV | Thermal strain intensity or thermal equivalent strain. |
| EPSW | Swelling strain. | |
| NL | SEPL | Equivalent stress (from stress-strain curve). |
| " | SRAT | Stress state ratio. |
| " | HPRES | Hydrostatic pressure. |
| " | EPEQ | Accumulated equivalent plastic strain. |
| " | PSV | Plastic state variable. |
| " | PLWK | Plastic work/volume. |
| TG | X, Y, Z | Component thermal gradient. |
| TF | X, Y, Z | Component thermal flux. |
| PG | X, Y, Z | Component pressure gradient. |
| EF | X, Y, Z | Component electric field. |
| D | X, Y, Z | Component electric flux density. |
| H | X, Y, Z | Component magnetic field intensity. |
| B | X, Y, Z | Component magnetic flux density. |
| FMAG | X, Y, Z | Component electromagnetic force. |
Entity = ELEM, ENTNUM = n (element number) | ||
| Valid labels for element results are: | ||
| Item1 | IT1NUM | Description |
| ETAB | Lab | Any user-defined element table label (see ETABLE command). |