Controls the solution printout.
Item for print control:
Basic quantities (nodal DOF solution, nodal reaction loads, and element solution) (default).
Nodal DOF solution.
Nodal reaction loads.
Element nodal loads. When nonlinear stabilization is active, the stabilization force/moments are also printed.
Stabilization force/moment at the applicable nodes (valid only when nonlinear stabilization is active).
Element energies. When nonlinear stabilization is active, the energy dissipation due to stabilization is also printed.
Nodal velocity (applicable to structural transient analysis only (ANTYPE,TRANS)).
Nodal acceleration (applicable to structural transient analysis only (ANTYPE,TRANS)).
All of the above solution items.
Print solution for this item
Freqth (and the last) substep of each load step. If -
n, print up to
n equally spaced solutions (only applies to static or full transient
analyses when automatic time stepping is enabled). If NONE, suppress
all printout for this item for this load step. If ALL, print solution
for this item for every substep. If LAST, print solution for this
item only for the last substep of each load step. For a modal analysis,
use NONE or ALL.
Name of the component, created with the CM command, defining the selected set of nodes or elements for which this specification is active. If blank, the set is all entities.
Note: The component named must be of the same type as the item, i.e. nodal or element. A component name is not allowed with the BASIC or ALL labels.
Controls the solution items to be printed, the frequency with which they are printed (in static, transient, or full harmonic analyses), and the set of nodes or elements to which this specification applies (in static, transient, or full harmonic analyses). An item is associated with either a node (NSOL, RFORCE, V, and A items) or an element (all of the remaining items). The specifications are processed in the order that they are input. Up to 50 specifications (OUTPR and OUTRES commands combined) may be defined. Use OUTPR,STAT to list the current specifications and use OUTPR,ERASE to erase all the current specifications.
As described above, OUTPR writes some or
all items (depending on analysis type) for all elements. To restrict
the solution printout, use OUTPR to selectively
Freq = NONE) the writing of solution
data, or first suppress the writing of all solution data (OUTPR,ALL,NONE) and then selectively turn on the writing
of solution data with subsequent OUTPR commands.
If the generalized plane strain feature is active and OUTPR is issued, the change of fiber length at the ending point during deformation and the rotation of the ending plane about X and Y during deformation will be printed if any displacement at the nodes is printed. The reaction forces at the ending point will be printed if any reaction force at the nodes is printed.
Nodal reaction loads (
Item = RSOL)
are processed according to the specifications listed for the PRRSOL command.
Result printouts for interactive sessions are suppressed for models with more than 10 elements.
This command is also valid in PREP7.