**SET**, * Lstep*,

`Sbstep`

`Fact`

`KIMG`

`TIME`

`ANGLE`

`NSET`

`ORDER`

Compatible Products: – | Pro | Premium | Enterprise | Ent PP | Ent Solver | DYNA

`Lstep`

Load step number of the data set to be read (defaults to 1):

`N`

—

Read load step

.`N`

**FIRST**—

Read the first data set (

and`Sbstep`

are ignored).`TIME`

**LAST**—

Read the last data set (

and`Sbstep`

are ignored).`TIME`

**NEXT**—

Read the next data set (

and`Sbstep`

are ignored). If at the last data set, the first data set will be read as the next.`TIME`

**PREVIOUS**—

Read the previous data set (

and`Sbstep`

are ignored). If at the first data set, the last data set will be read as the previous.`TIME`

**NEAR**—

Read the data set nearest to

(`TIME`

is ignored). If`Sbstep`

is blank, read the first data set.`TIME`

**LIST**—

Scan the results file and list a summary of each load step. (

,`KIMG`

,`TIME`

, and`ANGLE`

are ignored.)`NSET`

`Sbstep`

Substep number (within

). Defaults to the last substep of the load step (except in a buckling or modal analysis). For a buckling (`Lstep`

**ANTYPE**,BUCKLE) or modal (**ANTYPE**,MODAL) analysis,corresponds to the mode number. Specify`Sbstep`

= LAST to store the last substep for the specified load step (that is, issue a`Sbstep`

**SET**,,LAST command).`Lstep`

If

= LIST,`Lstep`

= 0 or 1 lists the basic step information.`Sbstep`

= 2 also lists the basic step information, but includes the load step title, and labels imaginary data sets if they exist.`Sbstep`

`Fact`

Scale factor applied to data read from the file. If zero (or blank), a value of 1.0 is used. This scale factor is only applied to displacement and stress results. A nonzero factor excludes non-summable items.

Harmonic velocities or accelerations can be calculated from the displacement results from a modal (

**ANTYPE**,MODAL) or harmonic (**ANTYPE**,HARMIC) analysis. If= VELO, the harmonic velocities (v) are calculated from the displacements (d) at a particular frequency (f) according to the relationship v = 2 πfd. Similarly, if`Fact`

= ACEL, the harmonic accelerations (a) are calculated as a = (2 πf)`Fact`

^{2}d.If

= LIST in an analysis using rezoning,`Lstep`

across all rezoning data sets is listed.`Fact`

`KIMG`

Used only with complex results (harmonic and complex modal analyses).

**0 or REAL**—

Store the real part of complex solution (default).

**1, 2 or IMAG**—

Store the imaginary part of a complex solution.

**3 or AMPL**—

Store the amplitude

**4 or PHAS**—

Store the phase angle. The angle value, expressed in degrees, will be between -180° and +180°.

`TIME`

Time-point identifying the data set to be read. For a harmonic analyses, time corresponds to the frequency.

For a buckling analysis, time corresponds to the load factor.

Used only in the following cases: If

= NEAR, read the data set nearest to`Lstep`

. If both`TIME`

and`Lstep`

are zero (or blank), read data set at time =`Sbstep`

.`TIME`

Do not use

to identify the data set to be read if you used the arc-length method (`TIME`

**ARCLEN**) in your solution.If

is between two solution time points on the results file, a linear interpolation is done between the two data sets (except in rezoning).`TIME`

Solution items not written to the results file (

**OUTRES**) for either data set will result in a null item after data set interpolation.If

is beyond the last time point on the file, the last time point will be used.`TIME`

If

is between two solution time points and both`TIME`

and`Lstep`

are zero (or blank), no interpolation is performed for the`Sbstep`

**PRCINT**/**PLCINT**commands. (That is, for results generated by the**CINT**command, only the data set associated with the lower of the solution time points is used.)`ANGLE`

For harmonic elements (PLANE25, PLANE75, PLANE78, PLANE83, and SHELL61),

specifies the circumferential location (0.0 to 360°) used when reading from the results file. The harmonic factor (based on the circumferential angle) is applied to the displacements and element results, and to the applied constraints and loads which overwrites any values existing in the database. If`ANGLE`

= NONE, all harmonic factors are set to 1 and postprocessing yields the solution output.`ANGLE`

When using

= NONE with`ANGLE`

> 0, the combined stresses and strains are not valid.`MODE`

The default value of

is 0.0; however if the`ANGLE`

**SET**command is not used, the effective default is NONE.For full harmonic analyses with the amplitude option (

= 3 or AMPL),`KIMG`

is the prescribed phase angle at which the amplitude is computed.`ANGLE`

`NSET`

Data set number of the data set to be read. If a positive value for

is entered,`NSET`

,`Lstep`

,`Sbstep`

, and`KIMG`

are ignored. Available set numbers can be determined by`TIME`

**SET**,LIST.`ORDER`

Key to sort the harmonic index results. This option applies to cyclic symmetry buckling and modal analyses only, and is valid only when

= FIRST, LAST, NEXT, PREVIOUS, NEAR or LIST.`Lstep`

**ORDER**—

Sort the harmonic index results in ascending order of eigenfrequencies or buckling load multipliers.

**(blank)**—

No sorting takes place.

Defines the data set to be read from the results file into the
database. Various operations may also be performed during the read
operation. The database must have the model geometry available (or
use the **RESUME** command before the **SET** command to restore the geometry from **Jobname.DB**). Values for applied constraints [**D**] and loads
[**F**] in the database will be replaced by their corresponding
values on the results file, if available. (See the description of
the **OUTRES** command.) In a single load step analysis,
these values are usually the same, except for results from harmonic
elements. (See the description of the * ANGLE* value above.)

In an interactive run, the sorted list (* ORDER* option) is also available for results-set reading via a GUI pick
option.

You can postprocess results without issuing a **SET** command if the solution results were saved to the database file
(**Jobname.DB**). Distributed ANSYS, however, can only postprocess
using the results file (for example, **Jobname.RST**) and cannot use the **Jobname.DB** file since no
solution results are written to the database. Therefore, you must
issue a **SET** command or a **RESCOMBINE** command before postprocessing in Distributed ANSYS.

When postprocessing amplitudes or phases (* KIMG* = AMPL or PHAS):

The only appropriate coordinate system is the solution coordinate system (

**RSYS**,SOLU). For layered elements, a layer (**LAYER**) must also be specified. When displaying the displacement amplitudes, use a contour display (**PLNSOL**command). Because a deformed shape display (**PLDISP**command) could lead to a non-physical shape, the displacement scaling is off by default (**/DSCALE**,,OFF).The conversion is not valid for averaged results, derived results (such as principal stress/strain, equivalent stress/strain, and USUM), or summed results obtained using

**FSUM**,**NFORCE**, and**PRNLD**.Cyclic symmetry results are not supported.